Have you got CAD in any form? Can it export a DXF file? If you have answered yes to both of these it may be worth using a simple DXF to Gcode CAM program to create your Gcode. The one I use is Estlcam. This is available for download and can be used a number of times before you get a nagging to buy it. It takes a small amount of time to be able to use it easily but it is worth spending some time with it for relatively simple jobs like this.
I also do not understand why the circular path has been divided into three segments when a single line of code can replace the three arcs you have used.
G52 X 0.01 Y .6125
(thru hole)
(1ST PASS)
G1 F146 X0.0095 Y0.0
G1 F52 Z-0.34 X0.2095
G2 F40.0 X0.2095 y0 I-0.2095 J0.0
This makes it easier to understand and to change to climb milling you just need to change the G2 to G3
Another option is to arc into the start position by changing the line?G1 F52 Z-0.34 X0.2095 to G2 F40 Z-0.34 X0.2095 I0.1 J0
This could all be followed by an arc out as well G2 F40 Z0 X0.0095 I-0.1 J0
G52 X 0.01 Y .6125 (thru hole) (1ST PASS) G1 F14 X0.0095 Y0.0 G2 F40 Z-0.34 X0.2095 I0.1 J0 G2 F40.0 X0.2095 y0 I-0.2095 J0.0 G2 F40 Z0 X0.0095 I-0.1 J0
The arc in and arc out avoids dwell at the start and finish of the hole to keep it smooth
Martin
